Incorrect Missing Drill File error

[guillermo.gallo]

Hi, I am also a victim of this false positive error. I tried adding tree versions of the drill file with obvious names and supposedly recognized extensions but the error keep popping up. Very frustrating!

The file name matching algorithm sucks. Even files with obvious names like SILKSCREEN_TOP.GBR gets assigned to TOP COPPER!.

The second annoying thing is that even after reassigning the drill file to the correct category the upload remains unqualified for DKRED. Very frustrating!
ifboard.zip (19.5 KB)

[Kristof_2649]

Thank you for your inquiry.

I uploaded your board and had similar errors.

Your included drill file, looking at the drill size definitions and drill file tool selection something doesn’t look right.

If you look at my below drill file example T1C0.0236 would be the drill size definition and then in the below code everywhere T1 gets declared that physical hole location that size gets drilled.

M48
; DRILL file {KiCad (6.99.0-4976-g75a4de4744)} date Wed May 3 12:20:13 2023
; FORMAT={-:-/ absolute / inch / decimal}
; #@! TF.CreationDate,2023-05-03T12:20:13-05:00
; #@! TF.GenerationSoftware,Kicad,Pcbnew,(6.99.0-4976-g75a4de4744)
; #@! TF.FileFunction,Plated,1,2,PTH
FMAT,2
INCH
; #@! TA.AperFunction,Plated,PTH,ViaDrill
T1C0.0236
; #@! TA.AperFunction,Plated,PTH,ComponentDrill
T2C0.0315
; #@! TA.AperFunction,Plated,PTH,ComponentDrill
T3C0.0354
; #@! TA.AperFunction,Plated,PTH,ComponentDrill
T4C0.0374
; #@! TA.AperFunction,Plated,PTH,ComponentDrill
T5C0.0433
; #@! TA.AperFunction,Plated,PTH,ComponentDrill
T6C0.0512
; #@! TA.AperFunction,Plated,PTH,ComponentDrill
T7C0.0591
; #@! TA.AperFunction,Plated,PTH,ComponentDrill
T8C0.0630
%
G90
G05
T1
X3.2283Y-3.2579
X3.2283Y-3.9567
X3.2283Y-4.1535
X3.2323Y-3.6378
X3.2382Y-2.9528
X3.3661Y-3.6417
X3.4134Y-2.9055
X3.4449Y-4.1142
X3.5354Y-3.7795
X3.5827Y-2.9528
X3.5925Y-3.2579
X3.622Y-3.4646
X3.6339Y-3.748
X3.689Y-3.6417
X3.8268Y-3.5512
X3.8583Y-3.4646
X4.813Y-3.4646
X4.9803Y-3.4646
X4.9902Y-3.248
X5.0Y-2.9528
X5.0984Y-3.9685
X5.1063Y-4.2283
X5.1673Y-3.376
X5.1693Y-2.9094
X5.3346Y-2.9528
X5.3445Y-4.1535
X5.3543Y-3.2579
X5.3543Y-3.6417
T2
X3.3169Y-3.313
X3.4252Y-3.4526
X3.4252Y-3.551
X3.5138Y-3.313
X4.0157Y-3.4565
X4.0157Y-3.5549
X4.0157Y-3.6909
X4.0157Y-4.0909
X4.6Y-3.54
X4.6Y-3.94
X4.74Y-3.54
X4.74Y-3.94
X4.8819Y-3.5394
X4.8819Y-3.9394
X5.0197Y-3.5402
X5.0197Y-3.9402
X5.0689Y-3.3
X5.1673Y-3.4547
X5.1673Y-3.5531
X5.2657Y-3.3
T3
X5.02Y-4.0742
X5.02Y-4.1742
X5.1772Y-3.7598
X5.1772Y-3.8386
X5.1772Y-3.9173
T4
X3.3646Y-2.9705
X3.3646Y-3.0705
X3.3646Y-3.1705
X3.4646Y-2.9705
X3.4646Y-3.0705
X3.4646Y-3.1705
X5.1181Y-2.9695
X5.1181Y-3.0695
X5.1181Y-3.1695
X5.2181Y-2.9695
X5.2181Y-3.0695
X5.2181Y-3.1695
T5
X4.2Y-3.4766
X4.3Y-3.4766
X4.4Y-3.4766
T6
X3.3465Y-4.0551
X3.5433Y-4.0551
T7
X5.1772Y-3.6772
X5.1772Y-4.0
T8
X3.4469Y-3.7205
X3.4469Y-3.9587
X3.6319Y-3.8386
X3.7992Y-3.6575
X3.7992Y-4.1575
T0
M30

[Kristof_2649]

If you’re using Allegro in NC Parameters make sure to select →

Enhanced Excellon Format

And in NC Drill Select →

Auto Tool Select

Repeat Codes

[Kristof_2649]

Customer was kind enough to provide screenshots from OrCad PCB (Allegro) 17.4-2019 S024 that worked for them to fix this issue, see below: